The G01 command is used to move one or more axes to a specified position at a defined feedrate.

If multiple axes are specified, they will move together in a straight line and arrive at the target position at the same time.
Axes can be linear, rotary, or a combination of both.

G01 is a modal command and belongs to Group 1.

Syntax & Parameters

G01 followed by the axis (or axes) you want to move and their target coordinates.
Multiple axes can be specified on the same line.

Axis Parameters

• X, Y, Z, A, B Value
  Moves the specified axis to the given position using the current machine units.

• U, V, W Value
  Performs an incremental move on the X, Y, or Z axis while the machine is in G90 Absolute mode.

  • U - X axis

  • V - Y axis

  • W - Z axis
     

     

• F Value
  Defines the feedrate at which the axes will move.
  If no F value is specified, the feedrate from the previous G01 command is used.

Example Program

N10 G21
N20 G01 X10 Y20 Z30 F100
N30 G01 X0 Y0 Z0

Explanation:

• G21 sets the machine units to millimetres.

• Line 2 moves the axes to X 10 mm, Y 20 mm, Z 30 mm in a straight line at a feedrate of 100 mm/min.

• Line 3 moves the axes back to X 0 mm, Y 0 mm, Z 0 mm at the same feedrate (100 mm/min).